Effortless case fits that work the first time. Just drop a Sick of Beige PCB template on an Eagle schematic to get an optimized board that's ready to fit a case. Grab the library for Cadsoft Eagle below, other formats coming soon.

Effortless case fits that work the first time. Just drop a Sick of Beige PCB template on an Eagle schematic to get an optimized board that's ready to fit a case. Grab the library for Cadsoft Eagle below, other formats coming soon.

Latest revision as of 17:00, 26 July 2012

Contents

Overview

Are you sick of beige project boxes that hide your cool board and hard work? Wouldn't it be cool if your project was case ready from the first revision? The goal of our standard PCB format is to make it super simple to design a project that fits in a bunch of different cool cases.

We worked with case designer David Moberly (dsm) to create a case-friendly PCB footprint for all our projects. We call the specification Sick of Beige v1.0. Just drop a Sick of Beige PCB symbol on an Eagle schematic to get a board with nice rounded edges, mounting holes, and recommendations for connector placement.

The PCB templates come in two shapes, sized to fit the free version of Eagle and the various inexpensive PCB services. Read on for the full specification, or grab the library and get started with standard boards today.

PCB templates

Effortless case fits that work the first time. Just drop a Sick of Beige PCB template on an Eagle schematic to get an optimized board that's ready to fit a case. Grab the library for Cadsoft Eagle below, other formats coming soon.

Our Eagle footprint includes a 3mm radius 41 tRestrict and 42 bRestrict with its center on each 4 holes, and additional corner keepouts.

Edge keepout

We recommend minimum 1.7mm edge keepout for case clearance. Some cases may use rails, fingers, or bumps to hold the PCB in place by the edge. Components closer than 1.7mm may interfere with the mounting mechanism.

Our Eagle footprints include a 1.7mm width 39 tkeepout and 40 bkeepout around the board edges.

Reference markings

Our Eagle PCB footprints have other reference markings we found handy.

Center line

A center line makes it easy to align connectors.

The line is on layer 49 Reference, so it will not normally be on the final PCB.

USB-MINIB placement

A cross 5.25mm from the edge marks the correct placement for the USB-MINIB connector in our part library.

The line is on layer 49 Reference, so it will not normally be on the final PCB.

Board size

The board size in the format DPXXYY_v1 is included on the back in the lower right. The text is 1.27mm size, 12% ratio.