How to create a kelvin symbol in Dxdesigner

I'm try to drawing a Kelvin connection for my schematic. that's mean, I want to short the different nets together.

I would like to create a invented Kelvin symbol, one side connect to a net, and the other side connect to different nets, but when forward, the symbol do not forward into the PCB but those nets short together in the PCB.

I have tried a few things, one is just to draw a copper line between two different pads in the footprint. The footprint editor doesn't complain about it, but on the board, it doesn't allow me to route those pins with DRC on. And the DRC check doesn't like it either.

We need a way to tell layout to allow those "shorts" when they are created as part of the footprint. Since it allows bridging copper, is there some way to treat those shorted pads as bridged?

Which is the other way I've done it - just create the footprint with the kelvin connection pads isolated from any other copper. When the part is placed on the PCB, add a copper "bridge" to connect the Kelvin pads to the main pads. Obviously the problem with this is that you have to remember to add the bridge copper. It is way too easy to forget, and then the board is no good.

I am sorry that I did not response to your sample request. 2 pictures attached. I actually created PADS component specially for Kelvin use with 2 pads shorted between them and called it "virtual jumper". (see the blue component). It is funny to put component on PCB just because DxD does not know to handle such situation, but it works.

I will be glad to hear another idea.

Benny

Attachments

In PADS Layout you can create a copper and make it a Copper Bridge and this will allow you to assign more than one net to copper thus shorting two or more nets together. Electrically these nets are separate but in layout are shorted together. Running Clearance check will not report shorts.